- 4-1 Introduction
- 4-2 Third- and First-Angle Projections
- 4-3 Fundamentals of Orthographic Views
- 4-4 Drawing Orthographic Views Using SolidWorks
- 4-5 Section Views
- 4-6 Drawing a Section View Using SolidWorks
- 4-7 Aligned Section Views
- 4-8 Broken Views
- 4-9 Detail Views
- 4-10 Auxiliary Views
- Chapter Projects
This chapter is from the book
This chapter is from the book
This chapter is from the book
4-4 Drawing Orthographic Views Using SolidWorks
SolidWorks creates orthographic views using the drawing tools found on the New SolidWorks Document box. See Figure 4-27.
)
Start a new drawing by clicking the New tool.
Click the Drawing icon on the New SolidWorks Document box.
Click OK.The Sheet Format/Size box will appear. See Figure 4-28. Accept the A (ANSI) Landscape format.
Click OK.A drawing template will appear. See Figure 4-29. The template includes a title block, a release block, a tolerance block, and two other blocks. The template format can be customized, but in this example the default template will be used. The title block will be explained in the next section.
Click the Objects tool.
Select the object option.See Figure 4-30.
The Document Properties dialog box will appear. See Figure 4-31.
Click OK.Third-angle projection is the format preferred by U.S. companies in compliance with ANSI (American National Standards Institute) standards. First-angle projection is used by countries that are in compliance with ISO (International Organization for Standardization). Figure 4-32 shows an L-bracket drawn in both first- and third-angle projection. Compare the differences in the projected views.
Figure 4-32 also shows a dimensioned isometric drawing of the L-bracket. The bracket was drawn in Section 3-3. If you have not previously drawn the bracket, do so now and save it as L-bracket.
Click the View Layout tab.
Click the Standard 3 View tool located on the View Layout panel.See Figure 4-33. The Standard 3 View PropertyManager will appear on the left side of the screen.
Figure 4-33
Click the Browse. . . box.The Open box will appear. See Figure 4-34.
Select the L-BRACKET file. A rectangle will appear on the screen representing the views.
Select the L-bracket, and click Open.Three orthographic views will appear on the screen. They include no hidden lines. The hidden lines must be added. See Figure 4-35.
Click the top orthographic view and select the Hidden Lines Visible tool in the Display Style box of the Drawing View PropertyManager.The hidden lines will appear in the top view.
Click the right-side view, then click the Hidden Lines Visible tool to add hidden lines to the right-side view.Notice in the top and right-side views that there are no centerlines for the hole. Centerlines are added using the Centerline option found on the Annotation tab. See Figure 4-36. The circular view of the hole will automatically generate a set of perpendicular centerlines.
Note the difference between center marks and centerline tools.
Click the arrow on the right side of the Annotation panel and select the Centerline option.
Click each of the two parallel lines in the top and side views that define the hole.
)
)
)
)
)
)
)
)
)
)
The centerlines will appear. See Figure 4-37.
)
Figure 4-38 shows the orthographic views of another object. The dimensions for the object are given in Figure P4-23. Note the hidden lines in the side view that represent the Ø30 hole. The right vertical line is continuously straight, whereas the left vertical line has a step. Why?
)
To Move Orthographic Views
Figure 4-39 shows the orthographic views of the L-bracket generated for Figure 4-37. The views can be moved closer together or farther apart.
)
- Move the cursor into the area of the top view.
A red boundary line will appear.
- Click and hold one of the boundary lines.
- Drag the view to a new location.
To Create Other Views
The Standard 3 View tool will generate front, top, and right-side orthographic views of an object. These views are considered the standard three views. Other orthographic views and isometric views can be generated.
- Click the Projected View tool.
The Projected View tool is one of the View Layout tools.
- Click the front view and move the cursor to the left of the front view, creating a new orthographic view.
In this example a left-side view was created. Add hidden lines and centerlines as needed.
- Click the left view in its new location.
- Press the <Esc> key or click the green OK check mark.
See Figure 4-40.
- Use the Centerline tool to add a centerline to the hole in the left-side view.
- Click the Projected View tool and click the front view again.
- Move the cursor to the right and upward.
An isometric view will appear.
- Click the isometric view in its new location.
- Press the <Esc> key or click the green OK check mark.
)
){kind=link}
){kind=link}